SolidWorks 2011 Parts Bible - Matt Lombard [214]
Creating Other View Types
SolidWorks is able to create any type of view that you need. If you can define what the view should look like, then SolidWorks can create it. The only limit is your creativity.
Using a Crop View
The Crop View is simply a view that looks like a Detail View without requiring a parent view. This feature enables you to reduce the number of views on a sheet and save some room. However, a cropped view may be confusing if it is not clear which area is being detailed in the cropped view.
Unlike Detail Views, in Crop Views the closed loop must be sketched in the view before you invoke the command. To make the Crop View, draw the closed loop as shown in Figure 15.15 in the image to the left, and then click the Crop View button on the drawing toolbar or access the command by choosing Insert⇒Drawing View⇒Crop.
To edit a Crop View, right-click the view, expand the arrow next to Crop View, and select either Edit Crop or Remove Crop. Removing the crop does not delete the sketch that the crop was created from.
FIGURE 15.15
A sketch loop and a Crop View
Using a Broken-out Section View
The Broken-out Section View is another view type that alters an existing view rather than creating a new view. It also requires a closed loop sketch. The Broken-out Section View is very useful in assembly views where parts are obscured by other parts, in particular when a set of parts is inside a housing and you want to show the inside parts without hiding the housing. Of course, you can also use Broken-out Section Views on parts with internal detail.
Broken-out Section Views act like a cut that is created from the drawing view. Any faces created by the cut are hatched. Figure 15.16 shows a casting part view using a Broken-out Section View. You can create Broken-out sections on parts or assemblies. You cannot create Broken-out Section Views using existing Detail, Section, or Alternate Position Views.
FIGURE 15.16
A Broken-out Section View
Notice that in Figure 15.16 the temporary axes for the flange holes are showing and cannot be turned off. This is probably a display bug and is present in SP0 of SolidWorks 2011.
The hatch pattern is associated with the materials assigned for each part. You can change the hatch scale by double-clicking a hatched region and using the settings in the dialog box shown in Figure 15.17. To change the hatch size, you have to deselect the Material Crosshatch option.
FIGURE 15.17
Changing the hatch pattern on a broken-out section
Broken-out Section Views require you to specify a depth for the break. You can use an edge selected from a different view or a distance to specify the depth. In the case of the broken-out section, the depth is into the screen, while with the regular section the section depth is measured as a distance perpendicular to the section line.
Drawing the closed loop
Broken-out Section Views are initiated from an existing view either with or without a pre-drawn closed loop. If the loop is pre-drawn, then you must select it before clicking the Broken-out Section toolbar button on the Drawings toolbar or accessing the command by choosing Insert⇒Drawing View⇒Broken-out Section.
If the view has no pre-drawn, pre-selected loop, then initiating the function activates the spline sketch tool. It is not necessary to use a spline as the closed loop for this view type, but Broken-out Section Views are traditionally created with a freehand sort of boundary, even when drawn manually.
If the loop is closed in an uninterrupted workflow, then after the last spline point is drawn, joining the spline back to itself, the Section Scope dialog box appears. This enables you to select any parts that are not to be sectioned if an assembly is in the sectioned view. It is customary to avoid sectioning shafts, screws, or other cylindrical components. Using the Section Scope, the image on the right in Figure 15.16 would be altered to look like the image on the